Join Leon van den Heever for an in-depth discussion in this video Splitting the connecting rod, part of Modeling a Motorcycle Engine with SOLIDWORKS.
- Next we will split the bottom cup from the main cone rod. Again, there are different ways we could go about doing this like severing out separate parts, but to keep things a bit simpler we will use configurations along with the split command to achieve our goal. Now select the configuration manager tab right beside the property manager tab. Let's create two new configurations by right-clicking on the part name in the tree and select add configuration. Name it cone rod and okay.
Do the same to add another config and let's name it cone rod cup. Remember that the suppress features option under the advanced options is currently active. If active new features added with other configurations active are suppressed on this configuration select okay, double-click the cone rod config to make it the active configuration. Do a search for the split command. Drag it to the features command bar for easy access.
Now let's run that command. In the trim tool selection box select the top line, which is where our model will be cut. Now select the cut part button. Under the resulting bodies select the tick box under the scissors column for item two only. Below that select the consume cut bodies option so that our selection will be consumed by the split command and let's say okay to that. The bottom cup portion of our model is now gone with only the main portion of our cone rod.
Activate the cone rod cup configuration. Go through the same procedure. So split command, select item one only with consume cut bodies selected and okay. We are now left with only the bottom cup. Activate each configuration to see the results. We've achieved our goal in a very efficient manner by doing this, so take the time to understand what we have just done and how it all works. The main profile of our cone rod is now complete. You can go ahead and to the relevant configuration add any additional detail that you like, maybe lubrication or grease ports, which the revolve cut or other tools we have already used would give the desired results.
I'll also leave it to you to add fillets or chamfers to each half to break any sharp edges where necessary. Use your discretion and reference your final result to my final model if needed. I'll save my final model as conerodfinal.sldprt. Remember to first activate the configuration you want to make changes to when doing that.
Need a better background in SOLIDWORKS before you can continue? Check out SOLIDWORKS 2014 Essential Training.
- Sketching the flywheel
- Building and cutting the flywheel shafts
- Filleting the flywheels
- Splitting the connecting rod
- Building the sprocket
- Modeling the camshaft
- Combining parts into an assembly