Join Gabriel Corbett for an in-depth discussion in this video Drawing view types, part of Cert Prep: Certified SOLIDWORKS Professional (2015).
- On the exam a lot of times there's going to be questions asking us to identify different drawing views so let's go through the basics so we make sure that we're familiar with all of them. First off I've got a top view of my part right here. I've already added that. Now I go up here to View Layout and I can click on Projected View which is going to take this and it's going to do a isometric projection to the right, to the top, to the bottom, to the right, or isometric. So in this case here I'm going to place it to the right.
Now next one. So I've got three standard views which automatically just put those three views in for us. If we didn't have a model in our assembly we can bring a model in by using that model view but most of the time you're going to click on the button that says "Make Drawing from Part" or "Drawing from Assembly" so you're not going to really need to bring in additional models unless you have multiple models on a drawing. So we already kind of covered those. Projected View we just did. Auxiliary View, if you've got something at a funny angle I can choose one of these auxiliary lines and then project along that line so notice I chose this face here or this little edge here to project. That's my Auxiliary View so that's a quick way to add that.
I'm going to delete it for right now though. Go into Section View. If I want to cut something in half and look inside, that says "section" to me so Section View. I can choose if I want to section it horizontally, vertically, or at some funny angle and in this case here I'm just going to section it right here and notice as soon as I do that it gives me this little dialogue box that shows a few different options here but if I click on "OK" it shows me a Section View right there where I want it. Now it's overlapping this other one here so let's move those over. But you can see I can cut into the material and you can see it's hatched now showing that I've sliced through the material at this location here called B-B and notice it's showing you it's a Section View here directly below that.
Anytime you see a Section View you're always going to see some kind of designator saying it's Section A-A, B-B, C-C, something along those lines so keep those in mind for Section View. Next one I'm going to look at is a Detail View. That means if I want to zoom in, almost like with a microscope, and look at a small detail of a part, not the entire part. So Detail View, I'm going to click on this. I'm going to zoom in on this area here so I can snap to a midpoint or an endpoint or a center or just arbitrarily, it doesn't really matter.
Click on this, I'm going to zoom in here and draw out a circle basically showing what I'm zooming in on and then I can see I can get that little small section and drop it directly below. So you can see I have Detail C and it's increasing the scale or magnifying the scale of that part of the drawing so once I have that Detail View now I can add dimensions there and I'm adding them in the zoomed-in view so I can see all those little fine details. Alright, next thing we want to do is a breakout section. That's going to be breaking into a model so we can see some details that we might not have seen otherwise.
So to do a breakout section, first things first, I'm going to draw a spline of where I want to look into so I'm going to make a little spline here around this corner of this part and then I'm going to define the depth. I can type in a value or I can choose something, like a feature in the part, to create the breakout section. So notice as I do that, it's actually breaking that material out and you can see just the very edge of that hole there that goes through the part.
This is not a very good example of a part here to use the breakout section on because there's not really that much information inside of here, but if there was, it would definitely be a great way to look inside that part. But for the exam we just need to understand what the different types of views are and why we might want to use them so for sure brush up on Section View, Detail View, and Breakout Section. We're also going to take a look at Break View and Crop View. Break View is for generally long parts. Say if you had a big long tube, it's 12 feet long but you had some details at the ends that you wanted to show, if you just brought it into a drawing normally it'd be this long long tube, you wouldn't see anything.
So I can slice it in half and bring it together. So again this is not really the best part to do that on but I can still use that tool, so Break Section. Here it is, I click on Break. I am going to choose this drawing view right here. And notice I can drag this little break anywhere inside of that part so I'm going to put it right here and then my next break's going to be over here and it just brings those two pieces together. So it makes it shorter so I can see the ends and I can zoom in on my part quite a big bigger.
That's really not what I want to add to this drawing so I'm going to click out of that and then undo, but it does give you an example of how to use the Break Section. Most of the time you're going to be using that on very long features like a piece of pipe or tubing, something like that where you have features at the ends and you want to show it a little bit closer. A Crop View is the ability to remove part of a drawing or part of a view so you're only seeing one small section. So let's click on Crop View and create a sketch of what I want to see. In this case here, maybe I only want to see this upper corner here, so I can choose a sketch.
And I'm going to say just this little circle right here is what I'm going to use for my sketch. And then I'm going to go back to Crop View. It's going to remove all the rest of the drawing besides what I see inside of that little Crop View. Again, not very useful for this part here but it does show you how you can remove a big portion of a drawing so you just see the detail part that you want to see. That's the Crop View. The last one is Alternative Position View. If you have something like a lever and it has multiple positions it can be in you might show it in the first position and then in Alternative Position View, showing maybe the off position or something like that.
Showing the two different configurations of where that lever can be. Generally your First Position View will be in full lines and then your Alternative Position View is going to be in a dash or dotted line. Those are our main layout views. Hopefully this is a great review on doing those things. Make sure you do go in and practice a few of these just to make sure you're up to speed with all these different views, how to use them and more importantly, how to recognize what they really are.
He also breaks down the three segments of the test (part modeling, configurations, and assemblies), providing strategies that will help you pass each section. At the end of the course, there are two sample exams to practice what you've learned.
- CSWP requirements review
- Working with sketch entities, tools, and relations
- Using the boss and cut features
- Performing sweeps and lofts
- Smoothing corners with Fillet and Chamfer
- Creating linear and circular patterns
- Setting up equations
- Creating multibody parts
- Setting mass properties
- Working with materials and constraints
- Inserting components
- Setting up reference geometry
- Arranging features to change the part
- Working with suppression states
- Using a design table to build configurations
- Establishing standard drawing views
- Annotating your drawings