In the Assembly Setting there are settings that can be adjusted to improve SOLIDWORKS performance.
- [Instructor] When adjusting your systems options in SOLIDWORKS another good area to adjust is the assemblies. Obviously assemblies have the biggest load on SOLIDWORKS and the most demand on your system, so let's check that out. I'm going to go up to Options, Systems Options, down to Assemblies. Now we're basically going to leverage every option that's available here. So moving down the list we want to check Prompt before changing mate alignments on edit, we're going to keep it checked to Optimize component placement when adding mates, we're going to allow the creation of misaligned mates, we're also going to check here Save new components to external files.
When you create a new part file in an assembly it gives you the option to change it as an external file or an internal file. When you save that as an internal file it just makes your assembly file bigger and when you're opening it, closing it, saving it, it's going to take more time and that stays in your RAM active. You can't really turn that lightweight, 'cause it's part of the assembly, it's saved internally. So we're going to have that option checked. And that'll make you save your new parts with new names and the correct location anyway.
Moving down the line, we're going to keep this unchecked, we're also going to keep this unchecked, the Automatically check and update all components. We don't want it to automatically do anything. Moving down below, for large assemblies we do want to use Large Assembly Mode, so we're going to check that. And I'm actually going to turn this down to 100. So this is the number of components in an assembly that'll prompt Assembly Mode to turn on. What that does is make it so when you open the assembly all of your files and sub-assemblies come in at lightweight mode and not all the features are pulled up, but as you go and open them and try to edit them the files are pulled up in your local cache and you're good to go.
If you're using mega huge assemblies, like facility layouts or something like that, you can also use the Large Design Review. But I'm not going to use that at this time. Moving down, When Large Assembly Mode is active we're going to use all of these options. We don't want it to save an auto recovery file, because that means it's going to be taking our file over a set period of time and just saving it over and over, which is going to slow us down. So we're going to keep that active. Do not rebuild with switching.
We're going to hide all the planes, axes, sketches, curves, annotations, basically hide all in the views. We're not going to display edges in a shaded mode. We're not going to preview hidden components. We're going to disable the verification on rebuild. Again, this is just more computation going on in the background and we want to turn that off. We're going to optimize the image quality for better performance. And we're going to suspend automatic rebuild. You can always just hit ctrl + q on your keyboard, this is a hotkey that makes it force rebuild the whole feature tree if you need to.
But otherwise there's no reason to keep reloading the feature tree over and over and rebuilding it while you need that demand for other processes. Also, down below you can, for Envelop Components automatically load in lightweight and just leave the Load read-only alone, because you want to be able to edit your assemblies. So you can see these are a lot of options that change for the assemblies, but this'll help you really, really speed things along. When you're done you just go ahead and hit OK and all your settings are loaded.
- How your workstation's hardware functions
- Adjusting System Options settings
- Modeling best practices
- Creating custom configurations
- Fixing your assemblies
- Using SpeedPak
- Increasing modeling performance with Instant2D and Instant3D