Learn how to add a forming tool to the library.
- [Instructor] Okay, so what if we wanted to create a forming tool from scratch? So, again, you can look through the types of forming tools that are available in SolidWorks and get some ideas from there, or you can just create your own forming tool right from the get-go. So, I'm going to start a new part. I'm going to make it metric, but ANSI standard, because I'm an American. I'm going to start in a Part file, because remember, we have to create our forming tools with part files.
And I'm going to start with this top plane. And you may recall that regardless of the way it is, you add the sheet metal, and then you take it away. So, I'm just going to create a little center rectangle, and I'm going to say it's 100 millimeters by 50 millimeters, and I'm just going to extrude it two millimeters. Okay. And then I'm going to add what I want my part to be.
So I'm going to start it on the top face like I did the others. And I'm just going to create like a rectangular extrude. Okay. And I'm going to extrude it up six, and I'm going to add... Actually, I want to add a little bit of a taper to it, of, say, five degrees, and then I'm going to add some fillets.
There, and the top face. And then I'm going to add some fillets along the bottom edge. And then I want to cut out everything but what's going to be used as my tool. So, I'm going to create a sketch and basically convert entities and extrude everything but my forming tool.
So, I've created it. I'm going to do a save as. I'm going to save it in my library under my forming tools, and I'm going to call it awesome rectangular emboss. Okay. And if you go to your sheet metal, you'll notice one of the things you can do is you can define something as a forming tool. So, it's going to ask me what my stopping face is going to be, and I'm going to click there.
And it's going to ask me if there are any faces to remove. I'm not going to remove any faces. And then I'm going to ask me for an insertion point, and I'm going to select that origin. And green check. And notice it'll ask me that I can use dimensions or relations to place the insertion point, but I'm not going to. Now, the other thing I can do also is I could add a center line or some kind of axis, but I'm not going to.
I'm just going to create it for now. Notice it's giving me the forming tool. It's colored my stopping face, and it's given me that yellow color. And I'm going to save it, and I'm going to close it. Okay. I still don't see it down here. But remember, if you click refresh, you'll see it. There's my awesome rectangular emboss. So let's test it out and see what it looks like. Okay. So I've placed it. Notice I can do a rotation angle here, and it'll rotate it.
And now I can use that center point to position it. There we go. Sometimes you have to make sure you select the right point. And I'm going to green check. And look at that, it worked. How cool is that? So how hard was it to create a forming tool? Not that hard.
- Adding a custom library to SOLIDWORKS
- Designing library folder locations
- Creating custom annotations for drawings
- Creating a grain direction annotation
- Modifying an existing forming tool
- Adding a forming tool to the Design Library
- Creating a hole pattern for a circuit board component
- Creating a feature to be reused
- Saving a feature to the Design Library
- Saving a block to the Design Library