Add in your sizes and locations with the dimensioning tool.
- [Instructor] Now that we have our views in place, we're going to start placing some dimensions. Now, in the dimensioning toolbar, go ahead and pull this out, get rid of my projections. What you'll see is you have several tools available to you. Typically, the one you want to use the most is going to be Dimensions, the first one. By double-clicking on it, the first thing I want you to notice is a Tools palette pops up. This is similar to the Sketch tools toolbar in that this is going to drive what you pick, how you pick, orientation of a dimension, pretty important to pay attention to this.
And now when I come in, I'm going to go ahead and pick this edge, and I'm going to measure all the way over to this edge. By picking those too edges, you'll notice on the Tools palette, I have what's called Force Dimension on Element. Basically, it's forcing a dimension between those two elements. I can pick a line if I want to have a line that's drawn at an off-angle or slightly off-kilter, maybe it's a vector direction that I need something to be measured up against. I can also specify do I want it as a projected dimension, true horizontal or vertical, or if I want to force it horizontal, do I want to force it vertical.
I also have on this toolbar, the ability to do intersection point detection, which I'll show you here in a minute. So let me go ahead and place this dimension. Now that I have the dimension placed, you're going to notice that it's at .55 feet. The reason why you're seeing it as feet is because of the page standard that I have. Now again, everyone's going to be working at a company that has their own standard. That standard is going to be determined by your admin group. Someone is going to have that defined for you, so you're not going to have to necessarily do this every single time.
What you'll probably have to do on occasion is change the dimension. I'm going to select the dimension. You'll notice up here it says FEET-INC. This is the actual type of dimension being displayed as feet. So if I select this down, and I go to NUMDMM, or NUMDNC, you'll notice I have two NUMDMMs. One is with a period, one is with a comma. Again, English standard versus a European standard or Japanese thing.
If I go to NUMDNC, if you wanted to get an inch. So if you want to see it in millimeter, you just go to NUMDMM, and we have our 169 millimeters. If I select that dimension once again, you'll notice that I have tolerances here as well. So you can adjust that tolerance quick and easy. I'm going to go back in and put in my dimension. And I want to measure from here to here. And you'll notice it goes back to feet, inch. And I cannot set this as a standard default.
V5 doesn't allow that. Again, it's the page setup that you have to get from your team lead or somebody, administrator, that created that initial page for you. So here I'm going to have to go back and change every single time, sometimes you're just going to have to. One thing you can do is just simply place all of your dimensions on the model. For example, maybe I want to put that dimension in. Maybe I want to place a few more of these dimensions in. Maybe I want to measure to an intersection point, so that intersection point goes from here to here.
And as I'm placing these dimensions in, again I'm not necessarily paying attention, to that magnitude as of yet. The reason behind that is that once I have my dimensions in place, I could just pick them all, I could go here, and specify all at once what magnitude I want. And it does it for me all at once. So even though yeah, it's a little frustrating, you can't change that to be a default, again that's based off of the standard that you're using, but you can go in, put them all in there, and then make the modification just once.
Clever little hint for you. Now, once again, I'm going to go in Dimensions. I can pick this outer edge. As I move this around, you'll see that it wants to give me a diameter. Maybe I don't want a diameter. What I can do is right mouse-click and again, this is very similar to the sketch, that's why I said earlier you really want to get familiar with that right mouse-click, you want to get familiar with the constraints. Looks a little different on the drawing but operates very similarly to what the sketch is doing. So for this, I want a radius.
Place that dimension. Now, I'm going to select this dimension, going to go to NUMDMM. If I have text that needs to be placed, or if I have any sort of options that need to be changed, I can right mouse-click over that text, I can go into Properties. Under Properties, you'll notice I have graphic. This is the color, line type. Here's the value. You'll notice that the value is orientation horizontal to screen.
Okay, so there's my NUMDMM. What's my precision? I have tolerance, so if you have tolerance that you need to have setup, TOL_RES2 for example, you can go plus minus, hit my Apply, now you can see what plus minus .1 looks like on the dimension. There's my dimension line, what type of dimension line? Do I have one part, two part, regular, with a leader? So all of those options are here.
What my extension lines look like, if I have a funnel. If I have any dimension text, so maybe I have something that is typical, and I need to specify Typical as a dimension text, hit my Apply and there it is. What type of font, size, as well as around that text do I have any symbols? So everything is there within your properties, so if you need to make a change to the text, you can quickly go through and do that.
If you need to change the format, you can quickly go through and do that under the Properties. Or, you can get familiar with some of these toolbars that do the exact same thing as you have within your properties, but you can do it all within the context of the toolbar, like the circle, so you can go back there and add your circles and your rectangles, your fonts, your text size, everything is located up here on those toolbars as well.
- Working with the CATIA v5 UI
- Understanding the menus
- Part visualizations
- Part design workflow
- Creating a sketch
- Basic editing
- Creating and editing sketch curves
- Part design
- Measures and analysis
- Building a project