Now that you have a part, you need to make the drawing. This first step is the initial setup of your drawing page.
- [Instructor] So we've gone to great lengths to design our part. Now, we need to go through and define the part. We're going to define the part in a drawing. So the first thing we're going to do is we're going to make sure we have our part open, and this is going to be the same for an assembly. If we're going to detail out the assembly, you have the assembly open. If you're going to detail out the part, you have the part open. Now that I have my part open, all I have to do is go into Start, Mechanical Design, and under Mechanical Design, you have Drafting.
As soon as I select Drafting, I'm going to get this new drawing creation wizard. What this wizard is asking is do I want an empty sheet? Do I want all views? Front, bottom, and right? Or front, top, and left? It's going to tell you global scale, the paper size, the format, and standard that's being used. Now, at this point, I'm just going to simply leave it as an empty sheet, and I'm going to come back and add the views in that I want.
So, I'm just going to select okay. Now that I have my empty sheet, you can see this is sheet one. In the tree, I have sheet one. Here's my drawing. I have a grid. If you don't like the grid, you can turn the grid off and the snapped point as well, there they are, sketch grid. If you like those, feel free to leave them on. Now, I have my drawing, I need to now begin importing in the views that I want. So for that, we're going to go over to our view toolbar, let me just go ahead and pull this out.
You'll notice that I have front. I have view from 3D, projections, auxiliary. These aren't going to be turned on until I get a view in. I have isometric view and then advanced front view. That's that view wizard sort of is talking about. Now, the first view that I'm going to use is going to be front view. Now, it doesn't mean it's going to be the front view. It means that whatever I bring in is going to be called the front view. The way I do this is I just simply go from Window, I switch over to the part that I want, and at this point, I just simply select a planar face or actual plane, I can pick it here, pick it here, anything basically planar.
Now I know these walls have draft on them, so I don't want to pick these because it actually can't. The view's just slightly one degree off from that wall. So I'm just going to go ahead and pick this plane out of the tree. As soon as I select it, what it does is it toggles back to the drawing, and it's asking how do you want to place this view? You'll notice in the upper right corner, I have a compass. Before I actually click anywhere, before I click somewhere on the page, if I come up to the compass, I can adjust the orientation of this any way that I want.
Once I get it where I want, all I have to do is click out on the page somewhere. Once I click out on the page, you'll notice that the view gets created and I have my front view scale, and I have several other things going on here. I have an axis system in the view. This is absolute off of the part, and you'll notice once again, it's called a front view. So it's not the actual front view off of the 3D. It's whatever you want front view to be.
Now with that, I'm just going to go into Tools, Options, and under Tools, Options, I'm going to go down to Drafting, and you can see I have a whole bunch of tabs for my drafting. So for the general layout, once again, you can turn on and off your grid. We've seen those buttons out here. If you like the blue axis system, you can leave that. If you don't like that, you can turn the display off.
My preference is not to have it. Just more stuff in the view I don't need to see. Under Layout, View Creation. On View Creation, what appears? Here's my front view and my scale. There's my scaling factor, view frame, my name. This is my view frame. You can turn that off, but I prefer to see it because it allows me to move the view easily. If I go into View, this is what gets generated automatically within the context of the view. And we'll talk about these some in the Properties.
Under Generation, this is for balloons, filters, and so on. Geometry, you have the capability of drawing geometry within a 2D drawing. Don't necessarily recommend it, but sometimes, you need to have an assist line or you got to draw something in at an intersection point that may not exist. For your Dimensions, this is how you control your associativity, how the dimension attaches to the cursor as it's being placed, when you're dimensioning to a circle, the default is for the center or to the edge.
Same thing for your chamfers, how you want chamfers to be represented. Manipulators, we'll talk about those here in a minute, but the manipulators are little icons that appear next to text and two dimensions. Annotations, this is, again, how you want your annotations. What are the linked to? References, how do they move on the screen? And Administration. This is for the administrator in your team. How do they want you to manage your drawings? Plain and simple, so you're really not going to mess around with the settings in here too much.
Select okay, and you'll notice that I did turn off that axis system, so that is now gone. This is going to stay here. I can delete it if I want to, but once I delete it, I have to put it in manually. So this is just additional text. If you want it, keep it. If you don't want it, you can just simply delete it. Now that I have my initial view in place, you'll notice that I have my projections. I have an auxiliary view. So for projection, I can just simply select it and roll the view out.
Click, and there it is. Now, one of the things you really have to pay attention to is based off of the standard on the page. If you're using an American or an English standard, it'll be in third angle projection. If it's a Japanese or German standard, sometimes you'll see first angle projection. Now, what I'm going to do is I'm going to go up to File, Page Setup. Now as you notice, I have my format set to A0 ISO.
Depending upon your administrator, they may have this changed to your local standard. Currently, I have ISO specified. I can change my standard, go to an ASME, and it's going to warn you, hey if you change it, anything that changed cannot be undone. So an undo is not possible once you change the standard. But with this, I can also specify the sheet size. Select okay. If I look at my actual sheet here, I can go into my properties.
You can see there's my sheet size, there's my format. You have different formats here as well that you can change, but that actual overall universal property that I set under file overrides everything. Now, you'll also see here within sheet that I have the ability to change the projection method. I know I have a first angle projection because when I rolled it out, I'm looking at the bottom. So if you need to change your projection method, you just come into the sheet, say third angle standard. You can also change the scale of the sheet.
So if you're dealing with a very large part, and you need to scale it to fit on your drawing, you can just come in here and say you want a one to five, a one to 10, one to 20 scale, whatever that may be. Or you can up it and say, "I want a two to one scale," because you're dealing with a very small part. You can give the sheet a name as well. So if you have a specific reference on a sheet, you can give it that name. That way, you know what you're looking at. Select okay, now, when I roll out my view, let me move this up, I'm just going to make another projection, you can see the difference.
So this was my bottom view off of a first angle projection. This is my top view off of a third angle projection. So it's these little things that you're going to have to pay attention to to make sure you get the view that you want. Now I can do another projection and roll it out off to the side. If I don't want a view, I can simply right mouse click and delete it. In a few quick and easy clicks, I can get views placed onto a drawing.
Now, you'll notice that the views are way off of the sheet. So I can just grab the actual main view, that front view, drag them, put them back onto the sheet, and as you can see, they really don't fit. So I'm going to go back to my sheet, right mouse click. I'm going to go into Properties. I'll go change the scale a little bit. Now that I've changed the scale, you can see I can fit them all onto the sheet. If you want to, you can go into the properties of the individual view as well, and here, you can individually change the scale of that view.
So it doesn't necessarily have to be a global scale change on the sheet. You can do it to the view, independent of the sheet.
- Working with the CATIA v5 UI
- Understanding the menus
- Part visualizations
- Part design workflow
- Creating a sketch
- Basic editing
- Creating and editing sketch curves
- Part design
- Measures and analysis
- Building a project