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SOLIDWORKS is the world leader in 3D software for product development and design. Start creating manufacturing-ready parts and assemblies, as well as detailed drawings and bills of materials. In this course, author Gabriel Corbett shows how to create 2D sketches that will become the basis for your 3D models. You'll use the Extrude and Revolve tools to turn 2D sketches into 3D parts, then create more complex geometry with sweep and lofts. Then learn how to use the cut features to remove material and shape parts, and use mirroring, patterning, and scaling to modify parts. Next, you'll combine parts into movable assemblies and subassemblies. Finally, you'll create accurately annotated drawings, complete with itemized bills of materials that relate the final parts and assemblies to a manufacturer.
The slot command is really nothing more than a straight or curved line in an offset entity, or a couple of circles and some curved lines. However, the slot command does really speed up the process of generating that type of geometry. To get started let's go ahead and start a sketch on the top plane. Start and sketch, and I'm going to go ahead and come up here to the sketch tool bar. And come under slot and go ahead and start with the straight slot option. First one, this case here. I'm going to click where I want to start and drag out a line and click where I want to end. Soon as I click, it now turns it into the slot and I can define either the radius or the diameter.
Click here, and then as soon I'm done with that, go ahead and click Escape. Then you can come up to smart dimension. Add dimension to the width to the slot. Maybe two inches across there and come up here for the other dimension of .5 and there's my slot. Now I can grab one of the end points. I could drag it around and maybe snap it at the origin or I can come and grab the mid-point and do the same thing. As soon as I snap around there, everything becomes fully defined. In black, it's fully defined, it knows exactly where it is. It knows it's location, orientation and rotation.
Okay, the next slot is a center point straight slot, there it is. Click where you want to start and then, as I drag this out, notice it gives me this kind of angle heads up display. So, that's a pretty unique way to create an angled slot. Click when you're done. And again, it turns it into a slot right away, and then I can go ahead and add a couple dimensions if I'd like. Dimension from here over to here. I'll type in .75 and I'll define the length of the slot of two inches. And then if I wanted to find the angle, what I can do is I can use maybe a construction line.
Start from one of the corners, click OK, and then add a dimension from that line to the other line to define the angle. If I want to tie this into the origin, what I can do is create a couple other construction lines. Start from one of these endpoints here, come down so I'm close to where I want to be. Or if I go a little further, it's okay as well. Click here. Click on to the origin and then make sure that I turn this line into a horizontal line. So I can define it very clearly. Now if I move this up, you can see those lines are always attached.
And then I can come over here and dimension the lines half inch. And over here, I'll type in five inches to define that shape and notice everything becomes fully defined. If I come up here, I came to the slot command. This time I come down to the three point arc slot. I want to click where I want to start and I want to click where I want to end and then third I'm going to define what that radius is going to be. So then I click, it creates the slot, and you go from there. If you wanted to find the angle of that slot you can use the center lines and start from one of the end points, go to the center of the radius and then back up to the other end point.
I could then type in a number to define that angle. Maybe you'll type in 80, click OK, and you can see the slot change. We could then define the center point or any other angles we want, using simple dimensions or relationships. The final type of slot is the center point arc slot, and you want to click right were you want to start in the beginning. And it shows you a little circle, showing you the major diameter radius of that slot. Once you click, then it gives you the option to define how much of that circle you actually want to use for the slot.
In this case here, I'm going to go to about 260 degrees, as soon as I click, it turns it into a slot, and I can just drag out the slot. Click OK, and again, I can dimension, or add some center lines from the endpoints to the center point to define the angle. I can set up some rotations. I could use, again if I put a center line here, I could define that maybe as a vertical line and then I can easily rotate this and move it around, do whatever I need to do with that slot. A couple great ways to create slots, makes it really easy versus having to draw all those lines individually or use the offset command.
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