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SOLIDWORKS is the world leader in 3D software for product development and design. Start creating manufacturing-ready parts and assemblies, as well as detailed drawings and bills of materials. In this course, author Gabriel Corbett shows how to create 2D sketches that will become the basis for your 3D models. You'll use the Extrude and Revolve tools to turn 2D sketches into 3D parts, then create more complex geometry with sweep and lofts. Then learn how to use the cut features to remove material and shape parts, and use mirroring, patterning, and scaling to modify parts. Next, you'll combine parts into movable assemblies and subassemblies. Finally, you'll create accurately annotated drawings, complete with itemized bills of materials that relate the final parts and assemblies to a manufacturer.
A drawing tablet contains a sheet format as well as these borders inside of a drawing. Making or choosing a template is an important in relaying the correct information about your part. A sheet template will have a block projection type and the units in scale. To get started, lets go ahead and open up 17.1-1 and we are going to make a drawing of this part here. So there is 2 ways to do that. Number 1 would be go up click on New, come down here to drawing and click on OK. Or if you cancel that out, I can go up to File, Make Drawing From Part, click on that.
Here's the default template. And go ahead and click on OK. Now, I'm going to choose this ANCC Drawing Format. And notice it just prepopulates it with a standard Sheet format which is called landscape C, which is right there. And we're going to go ahead and click on OK. And we can then drag in one of the views of our model, maybe a projection view. When we're done with that click on Escape and you can see at the bottom here I have a few pieces of information like the part description as well as the part number. But we're missing the block tolerance.
We don't have a logo. We don't have our company name filled out here. We're missing quite a bit of stuff. So I want to make changes to this sheet format, and I want them to save and be there the next time I open a drawing. So how do you do that? Well, first I want to show you what it looks like. So I'm going to jump over here, go back to my original part, and this time, I'm going to say, well, I want to start a new drawing. Make drawing from part. And choose the default template again. In this case, I'm going to choose a different sheet format. I'm going to click on browse. I'm going to come up here to desktop, down to exercise files.
Come over here to chapter 17 and notice I've got a sheet format called Two Trees. Click on OK, and then open that up. So now I have the same exact drawing, I can do the same thing. Drag out a couple of views, hit escape, but this time I have the logo, company information, block tolerance filled out. It's looking a lot nicer, and I don't have to do all that work over and over again. So, how do we do this? First things first, let's go back to the original format that we had. It doesn't have that information, and I want to modify the drawing sheet format. So to do that, I have to right click anywhere in the white space, and click on edit sheet format.
Notice everything turns blue, all these lines turn blue, and I'm in the regular sketch menu. So what I can do, is I can grab a line for instance, and I can move it around. I can drag these things out, I can reformat the whole design, as needed. I can add new lines if I want to. So I can do a lot of work here. To changes things around. But one of the first things I want to do, is add a picture. So notice, there's no icon up here for adding a picture, and that's a problem. So first, let's go and grab that picture tool. So under sketch, right click, and say customize command manager. Come over here to commands, and come down to the sketch tab, and notice there's a whole bunch.
Of tools that are available in the Sketch menu that aren't up here in the Ribbon. One of them happens to be this one here called Sketch Picture. And all I have to do is click on it and drag it up here and it docks into the Ribbon, and then I can use it. Also I want to point out while we're here is hey there's a bunch of other cool tools here to check out later on. Click on OK, and there's my sketch picture. Click on that. Notice I have this icon already preselected called exercise files, chapter 17, and it's called tt.png. Click on that one and click OK, and then we're going to be placing that into our drawing here.
Click OK again. And there's our logo. Double-click on it. You can change the size, you can change the aspect ratio, and you can also change the transparency. If you're using a .PNG file, it has a transparent background. You can click on From File, and it makes it transparent again. You can also grab the corners and make it smaller. You can move it around the screen. You can zoom in, scale it down to size, whatever you need to do. Place it wherever you want and then click on OK. Now if I want to add a few more lines, I can grab the line tool, connect the dots here, and border that in.
If I want to come over here and change some text, go ahead and click in the box, and maybe add for a 2 place decimal, we'll say .01, and for a 3 point decimal we'll say 0.005, and notice I clicked on this little symbol library. You can add some of this information as well, if need be. Go ahead and click Cancel, and there we go. Click OK. Now any other things we want to change, we can. When you're done with this, right-click again and say Edit Sheet, or you can click on this little icon here to get back to the original drawing view.
Now, I've made a few changes and now what I can do is save this out. So what I can do is go under File, Save Sheet Format, will actually save out that format, and where I want to save it at is on the Desktop, again, Exercise Files. Chapter 17 and notice I have that sheet form here called, Twotrees.slddrt, which is our drawing sheet format. So I could overwrite that if I wanted to but I already have it saved, so I'm not going to do it in this case, but you would be saving that out to some place in your file system. Now that it's saved, what I also want to do is save out a drawing template.
Now drawing template controls both the size, as well as a lot of the options built in behind the scenes. As far as these options up here, like our Units and how things are shown and our Annotations like Balloons and Datums. Well we can figure out all this information and define it all in a sheet format and a drawing template. And then every time we go back and open the part, open that drawing, all that information will be there. So, make any changes you want to make to the options. Then come over here to File, Save As. Instead of choosing a regular drawing, I want to choose make a drawing template.
Here it is, and notice here's my default drawing template stored within the SolidWorks folder. Or I can also come back here to Desktop. Come out here to exercise files. Jump down to chapter 17 and notice I've got a file already saved called tt.trdtot. It's a drawing template. And again I could over write the file if I wanted to and save that information. In this case, again I'm not going to save or over write the file because it was already created. But you would save it up. Click on cancel and we're back to our drawing view. Now there's one other thing I'd like to actually make a change to. Let's go ahead up here to Options, and come over here to File Locations.
In this case, I want to add a new path to where that new template is that I just saved. So I'm going to click on Add, and then I'm going to come to Chapter 17, and click OK. I'm going to actually add that path to that folder where that template now is. If I click on OK, it says, do you want to add this, I say Yes and then I want to go ahead and start a brand new drawing. Go up here to New. Notice I've got not only my original templates here, like a tutorial which I had there, but I also have this new tab called Chapter 17. And there it is, TT.
Click Okay, and boom, right away it opens up in that latest format with all that data. That I brought in from the sheet format as well as in the option changes I did in the drawing template and I'm good to go. SolidWorks has some built in templates that can be easily customized. Spending a few minutes and setting up your default template will put that professional polish in your drawings and make sure you're always relaying the correct information on your parts.
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