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SOLIDWORKS is the world leader in 3D software for product development and design. Start creating manufacturing-ready parts and assemblies, as well as detailed drawings and bills of materials. In this course, author Gabriel Corbett shows how to create 2D sketches that will become the basis for your 3D models. You'll use the Extrude and Revolve tools to turn 2D sketches into 3D parts, then create more complex geometry with sweep and lofts. Then learn how to use the cut features to remove material and shape parts, and use mirroring, patterning, and scaling to modify parts. Next, you'll combine parts into movable assemblies and subassemblies. Finally, you'll create accurately annotated drawings, complete with itemized bills of materials that relate the final parts and assemblies to a manufacturer.
Revisions are best handled at the part level, and we can link the drawing to that part revision. The custom properties of a part will generally have a revision property that can be filled out. From there, we need to make sure drawing template is linking to that property. Once we have the revision, we might also want to add a revision table to say what has changed and at what stage. In this case here, if I look at the bottom right hand corner of the drawing, I can see that I actually have a revision location. What I could do is come up here to Notes, I could type out a revision level and just drop it right there on the corner of my drawing.
Although, that would not be the best way to do so. So, go ahead and cancel that out. What we really want to do is go back to this part itself, and change the custom properties. So click on the part, click on Open Part. And I come up here to, File Properties, and come over here to Custom. So we're going to change a Custom Property. And notice over here on the Type a new property, if you click on that box and click on the drop down arrow. You can see, we already have a lot of custom properties already predefined here, and I can just choose one of them. One of those also happens to be Revision. So, as soon as I choose Revision, I can come over here, type in a or capital A, and there it is.
Also at this point in time, you probably want to add in maybe the description The material, part number, drawing number, check by, drawn by, all of this information here can be filled out and a lot of that will propagate through to your drawing. In this case here, we're focusing only on revision, so I'm just going to fill that out and click OK. Now, I go back over here to my sheet, and notice now, the bottom of the screen. Right here in the corner, I already have our Revision A. It's brought over from the part itself. So anytime I'm changing the part, we want to be rolling that revisions, so those latest changes will show up in the drawing.
Now I also might want to add a revision table display time. So I can click on Insert > Tables > Revision Table. Click on OK, and it will drop it up here on the upper right-hand corner of my screen. Now I can grab that and move it somewhere else if I wanted to, or I can also resize it or I can re-dock it again up here on the upper right-hand corner. If I'm ready to add a revision change, right-click and say Revisions. Add a Revision. Notice that automatically adds revision A with a certain date today's date. You can click in this box here, make whatever changes you want and note whatever changes those are, come over here, click on approved you can add your initials.
Let's go ahead and say GSC and there we go. Also if we wanted to, maybe increase the font, you can click on any one of these boxes here. You can over write the font, you can update it, you can make a link change, and you can format this however you see fit in your drawing standards. Revisions are very important in design, and even more important in manufacturing. Each time a part is changed the revision should be updated as well as the corresponding drawing. Failure to roll the revision on parts is a leading cause on manufacturing error from parts not being made or inspected to the latest changes.
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