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SOLIDWORKS is the world leader in 3D software for product development and design. Start creating manufacturing-ready parts and assemblies, as well as detailed drawings and bills of materials. In this course, author Gabriel Corbett shows how to create 2D sketches that will become the basis for your 3D models. You'll use the Extrude and Revolve tools to turn 2D sketches into 3D parts, then create more complex geometry with sweep and lofts. Then learn how to use the cut features to remove material and shape parts, and use mirroring, patterning, and scaling to modify parts. Next, you'll combine parts into movable assemblies and subassemblies. Finally, you'll create accurately annotated drawings, complete with itemized bills of materials that relate the final parts and assemblies to a manufacturer.
The Hole Wizard provides a quick way to generate a variety of standard size holes for screws, tapped holes, counter bores and the ability to change easily from one style to the other. The best way to use the Hole Wizard is preselect the plane, that you like to place the holes on. In this case here I'm going to choose the top of the part. Now under the Features tab, we have the Hole Wizard, just go ahead and click on that and it should launch the tool. Starting from the top here we have our hole specification. Down here, we can choose what type of hole we'd like to use. I can use counterboard, countersunk, just regular straight holes.
I can use tapped holes, piped tapped holes. I can define my own legacy type of hole, or I even have the ability now to use counterboard slots or countersunk slots or just a regular slots so some lot of nice tools available to us now within the whole wizard. Directly below that is our standard that we're going to be using, we have ANSI inch and we have all these other standards that we can be choosing from. So the most common are going to be inch or metric, and you can choose from those, in any of the styles of holes you'd like to use, in any of those categories.
Like a counterboard, countersunk or hole, or any of these other types. I'm going to choose ANSI inch, and then I can choose what style of hole. So for this case here, I can say, I'd like a socketed cap screw, or I can use any of these others. Starting with hex bolts or hex screws, panhead screws, all the way down. So take a look through the list. You have a lot of variety there to put it in. Also, below that, I have the size. I can choose any of the standard sizes for that style of screw. Notice as I scroll through them, you can see those were all available.
If I were to switch to a different style of hole. Maybe, up here, if I chose a tapped hole. Notice, all these categories change as well so I have a bottom tapped hole, or a straight hole, or just a regular tapped hole, and then I can choose the size of that tapped hole. So, all of these categories will change based upon what you choose in your original selection here at the top. I'm going to switch back to the counter porthole, socket head cap screw. We're going to choose a three ace, and my fit's going to be normal but you could change it to close or loose, or you can even modify it outside of that by choosing custom sizing and then type in those values.
These values here come from a table of your standard sizes for that type of screw, and, of course, you can override them, but generally, they're pretty good. End Condition can be Up to Next, Line through All, or any of these other choices here, but generally Up to Next works great because it will, in that feature all the way through the part without having to type in an exact number. You can also add a few other options, like head clearance, near side countersink, under head clearance and far side countersink. When you're ready to go ahead and actually place the hole, click on the next tab over called Positions.
And then I can choose to place that hole onto my sheet. Notice, as soon as I click, it places that hole. Anywhere I click now, it's going to automatically place the hole. What's really happening behind the scene here, is I have the point command turned on. So anywhere you see a point. Or anywhere Solid Works sees a point within Solid Works, it's going to put that same hole. Now, if I want to turn off placing holes, go up here and turn off the Point command. Or hit Escape. Notice, if I spin this around, these are just points. I can grab the point, I can move it around anywhere on the screen, or anywhere on that face.
In fact, I can even move it off of that face, although, that's really not going to help us out, but it is possible to do that, it'll probably give you an error. But anywhere on that face, you can place those holes and that's where it's going to be putting those holes. We're going to go over laying these holes out in the next couple of videos. And in this point here, I just want to go through the main steps for using the Hole Wizard and getting the holes into the part. And if you are happy with what you have. Go ahead and click OK. Click OK and you can see it places those counter board holes into the part, they go all the way through and they're easy to move around.
Now the great thing about using the hole wizard, is later on in your design, if you say, hey, I didn't want that size hole. I wanted these to be tapped holes. Don't worry. Go back to the Feature, click on Edit Feature, and switch over to tapped hole. Come over here, choose the size tapped hole. So in this case here, I'm going to go all the way down to that three A 16. Click OK, and they automatically update just that quickly. The locations stay the same, and the holes automatically change. And if you zoom in, you can see the hole has a little dotted line, showing that it's a tapped hole.
And by the way, when we go and make drawings of these parts later, all that data we put in, in the hole wizard will automatically propagate through to the drawing, showing the size, depth, and type of hole. The Hole Wizard is based on points, because the location of a hole is defined by a point, to add another hole, all we need to do is just add another point to the sketch. To change holes, go ahead and select a different style of hole, and all those holes will automatically update.
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