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Already up and running? This course is the next step in building your Autodesk Inventor skillset. Author John Helfen takes you through the interface and key processes of this parametric design system, including sketching, part modeling, assemblies, and drawings. Each process works in conjunction with the rest, allowing you to create parts and assemblies and document them in a way that they can be manufactured. Learn how to set up your project file; create and modify geometry; create extrusions, sweeps, and lofts; build parts with placed features and patterns of features; and create iParts and iFeatures. John also covers assembly visualization techniques, drawing views, and balloons and parts lists.
The course was created and produced by John Helfen. We're honored to host this training in our library.
Now that we've created the eye part, I want to show the power of the eye part actually working. And that takes place when you actually place the eye part into an assembly. Now, I know we haven't gotten to the assembly portion of the course yet, so it's not important that you understand everything about placing a component just yet. But what's important is that you see how an eye part reacts, when it's actually placed into an assembly because that's where the true power of the iPart comes in, where you have one single part that can generate as many different versions as there are rows in the table you just created.
To begin, we'll click New on the toolbar and select Standard.iam as the template. Then we'll click Create to start a new assembly file. With the new assembly file created, we're ready to place our iPart. We can go to Place on the toolbar or, we can right click in the graphics window and select Place Component. When the dialogue box comes up, you'll see in the exercise file that we have HandleComplete.ipt, that's our iPart factory. That is the main iPart that we created in the previous movie, that will generate additional parts based on each row in the table.
What's important here is that, the Only the Part is listed correctly. And the reason I call it out, is after we place this Part Inventor will create a folder at the same level, and it will store the variations of this part that the factory is generating in that folder. And I'll circle back to that at the end so you can see the outcome, after we've placed this part. I'm going to select handle.ipt and select open, now on the screen you can see the dialogue box for placing and ipart.
And this is different than a standard part. You won't get this ability with any part, it's really specific to an eye part, that you have the ability to select different versions. By default it's showing the keys, the length and height are the main keys for this item, we set that up in the previous movie. But what's important is that you have different options for tree views and table views. The tree view is very similar to what you saw in the browser in the previous movie. It essentially uses a tree structure to list all of the keys we set up when authoring the iPart.
And we can use this to select different variations of this specific model. You'll notice that as I select things, the different items update in the background, so you can see the preview update. Now, what I focus on is this table, it's the one I find most useful. It's essentially the exact same table you used to author the part itself. And I think it feels more like a catalog. So I can very easily see the difference between these. I can see that they go up and length, they also go up in height, and I can see how they're related to each other very easily.
So, I'm going to start with Part One, by selecting it with a left-click. And in the graphics window, i'll right click and select place grounded at origin. What that does, is places the part at the origin and locks it into place. And we'll learn more about this in the assembly portion. What's important here, is inventor automatically allows me to add additional items if I want to. If I need three of this type of handle, I can simply left-click and second and third time and get copies of that.
But, what I want to show here, is that I can also select item two, and place it and you'll notice that it's been updated based on it's size listed in this table, I'll select Item three. Move back over here on the graphics window and left click, and then again on item four, and move back into the graphics window and left click one more time. Now that we have all four items placed, we can dismiss. And you don't have to place every single item every time, obviously. What I'm doing here is using this as an example to show the different variations very clearly.
I'm going to go ahead and look at it from a front view, and organize these a little bit more clearly, and when we get into the assembly modeling portion of this course, we'll look at how we can use a constraints to place these and locate and locate them more accurately. But, you can clearly see that we have four different variations of this based on the table. Now what you'll also see is in the browser, we have each of these parts listed. And they show the I part icon. If we click the plus symbol to the left, and expand that you can see that the table is listed here.
So for item four, the largest of the handles, I could right click on this table and select Change Component, and I'm returned to that original dialogue box we used when placing it in the first place. So I could go back to the table, select item three and then hit okay and you see the model is updated accordingly. So at any point during your design process, once an iPart has been placed into an assembly you can simply right-click on that table to swap out the different versions that you've authored at any point.
Now, before I wrap this movie up, I want to go ahead and hit the Open dialogue box again and return to show the results of placing that eye part. When we first picked this part, this folder did not exist. So by placing this, what Inventor has done Is creating an individual part from that iPart factory and use the part name out of the table to name the part and place it in this folder. You can see here, we have Part2-01, -02, 3 and 4, which corresponds exactly with the parts listed here, Part2-01, 2, 3 and 4.
So, Inventor is going to work to help keep things organized for you as you're creating these iParts.
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